Trying to setup Auggie on cnc machine

[Cyrille]

Hello,

What do you think is my best path to convert my input files?
An external program?
Or using auggie's awsome (trully) ability to interpret input files?

Headers and the like asside, my files look like this:

TR,18000    // spindle speed  Gcode equivalent: ????
J2,0.000000,0.000000 // Jog: G01
J3,9.627712,105.045639,5.000000
M3,9.627712,105.045639,-1.000000 // feed G02
CG, ,6.040212,108.633133,0.000000,3.587494,T,1 // Arc G02/03

Creating a text processing program pauses no issues for me, but just checking if they was not an even lazier solution

Cyrille

[ArtF]

Wow, one horrible file.

  If it were me, Id write a post processor to deal with it, I dont
think Auggie will conform it easily to anything. Sometimes
you just have to make a hack.

Art

[Cyrille]

Hello,

Well, that is what I did... I wrote a "translator"...
However, since I never learned/wrote any G-Code, I have no idea if it is valid or not:-(

Here is what I generate. Does it look valid?

G21 G17 G90
S18000 M03 G04 P2

G0 Z20.000000
G0 X0.000000 Y0.000000
G0 X9.627712 Y105.045639 Z5.000000

G01 X9.627712 Y105.045639 Z-1.000000 F1518.000000

G02 X6.040212 Y108.633133 I0.000000 J3.587494 F3036.000000

G03 X32.130943 Y102.765289 I0.000000 J0.412506 F3036.000000

M05

Cyrille

[ArtF]

Cyrille:

  Looks to me like you cracked it fine.

Im in the process of adding a G38 for probing, and I notice I never turned on
tool length offset either, so Ill see if I can attach those hooks as well. Cant promise
anything at this point,but the process is underway.

Art

[ArtF]

Cyrille:

  The new G38 command seems to work well in rough testing. It is multiaxis
so one can probe with G38X10Y10Z-10 F100 and the axis will decelerate to a
stop when probe is hit. I havent done anything as yet with the hit point
data. One can I suppose set a tool by hitting a probe plate at F100, then do
an F10 , invert the probe signal and probe off with a Z move upwards. I think
I will add a way to zero to the probe hit data before I release it.

Art

[Cyrille]

Hello,

This sounds great...

Do you have an idea of the time between signal sensing and movement stop? Just to get an idea of the precision that can be obtained (not that I need too much anyway)?

Cyrille

[ArtF]

Cyrille:

  The way it works is the command G38 is interpreted as a G1 move, BUT the probe is set
to stop the move. We dont want to lose steps, so when the probe is hit, the Pokeys
automatically switches from Auggie's trajectory planner to its internal planner, takes control
and decelerates all axis to a stop using your max accel parameter. It then switches back to
Auggies planner.
  Auggie clears its g1 move from that point onwards, and receives a
position packet from the pokeys telling it where the probe hit at.

  I dont yet give access to the hit point. So if you do a g38 xyz..F100
you will be off the real zero by the deceleration distance of the f100 move,
so by then reversing the probe signal and probing off the point with
G38Z5F1 , you will stop when the probe releases.. and with f1 as the feedrate
youd probably be off by perhaps as little as 1 step. Perhaps less.

  Conversely you could simply do a g38Z-20F1 to start with
and get pretty much an exact zero.

Eventually Ill add a button to "Zero to Probe" where the zero will be
automatically set to a offset of the probe hit point. Pressing goto zero
will then zero you to the exact point.

Art
 

[Cyrille]

Hello,

OK, I understand now...

Obviously, the "probe to 0" is, ultimately, what I Was looking for, but I can always execute the G38, and then manually set the z axis at 0. it's not like it is a complicated operation, nor is it something that is done 10 times a minute!

Can one "script" gcode excution? I mean, I can, programatically tell auggie to execute some Gcode?

Cyrille

[ArtF]

Cyrille:

  I dont think I added a way to exectute a Gcode line from script. Though you can add
scripts to GCode. In Gcode a brace signifies a switch to script.

ex:

G0X10
{
  GlobalSet("ProbeInvert", 1 );
}
G1Y12X5

  Script can be injected to the Gcode this way. But I dont think I coded the other way to add
GCode to a script. Ill look into why I didnt, there may be technical reasons.
It may be I did add it though, Ill take a look in the code, it isnt something Ive used but
I added a great deal in there thats undocumented. 

Art

[ArtF]

Cyrille:

  I just confirmed I didnt add and script command to execute GCode. So Ill have to add a script
command to allow a G38 call. Pretty much anything else can be scripted with calls such
as Engine.ArcTo or FeedTo(.. ) etc..

  Probe however, is only accessable by Gcode, Ive been testing it in MDI calls. Hadnt occured
to me till you asked it needed to be called by script. You can invert the probe by script
but not the probe itself. I will add that before I release it.

Art